


{"id":39157,"date":"2026-11-16T20:44:44","date_gmt":"2026-11-16T12:44:44","guid":{"rendered":"https:\/\/www.bestpcbs.com\/blog\/?p=39157"},"modified":"2026-11-16T20:44:44","modified_gmt":"2026-11-16T12:44:44","slug":"pcb-copper-density-impedance","status":"publish","type":"post","link":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/","title":{"rendered":"PCB Copper Density: Why Matching Traces Measure Differently"},"content":{"rendered":"<div id=\"ez-toc-container\" class=\"ez-toc-v2_0_89 ez-toc-wrap-left counter-hierarchy ez-toc-counter ez-toc-grey ez-toc-container-direction\">\n<div class=\"ez-toc-title-container\">\n<p class=\"ez-toc-title\" style=\"cursor:inherit\">Table of Contents<\/p>\n<span class=\"ez-toc-title-toggle\"><a href=\"#\" class=\"ez-toc-pull-right ez-toc-btn ez-toc-btn-xs ez-toc-btn-default ez-toc-toggle\" aria-label=\"Toggle Table of Content\"><span class=\"ez-toc-js-icon-con\"><span class=\"\"><span class=\"eztoc-hide\" style=\"display:none;\">Toggle<\/span><span class=\"ez-toc-icon-toggle-span\"><svg style=\"fill: #999;color:#999\" xmlns=\"http:\/\/www.w3.org\/2000\/svg\" class=\"list-377408\" width=\"20px\" height=\"20px\" viewBox=\"0 0 24 24\" fill=\"none\"><path d=\"M6 6H4v2h2V6zm14 0H8v2h12V6zM4 11h2v2H4v-2zm16 0H8v2h12v-2zM4 16h2v2H4v-2zm16 0H8v2h12v-2z\" fill=\"currentColor\"><\/path><\/svg><svg style=\"fill: #999;color:#999\" class=\"arrow-unsorted-368013\" xmlns=\"http:\/\/www.w3.org\/2000\/svg\" width=\"10px\" height=\"10px\" viewBox=\"0 0 24 24\" version=\"1.2\" baseProfile=\"tiny\"><path d=\"M18.2 9.3l-6.2-6.3-6.2 6.3c-.2.2-.3.4-.3.7s.1.5.3.7c.2.2.4.3.7.3h11c.3 0 .5-.1.7-.3.2-.2.3-.5.3-.7s-.1-.5-.3-.7zM5.8 14.7l6.2 6.3 6.2-6.3c.2-.2.3-.5.3-.7s-.1-.5-.3-.7c-.2-.2-.4-.3-.7-.3h-11c-.3 0-.5.1-.7.3-.2.2-.3.5-.3.7s.1.5.3.7z\"\/><\/svg><\/span><\/span><\/span><\/a><\/span><\/div>\n<nav><ul class='ez-toc-list ez-toc-list-level-1 ' ><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-1\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#What_Is_PCB_Copper_Density_Near_a_Trace\" >What Is PCB Copper Density Near a Trace?<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-2\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#Why_Pressed_Prepreg_Thickness_Can_Change_Locally\" >Why Pressed Prepreg Thickness Can Change Locally<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-3\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#PCB_Stackup_Separate_Lamination_From_Return-Path_Changes\" >PCB Stackup: Separate Lamination From Return-Path Changes<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-4\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#PCB_Impedance_Calculator_Compare_Finished_Cross_Sections\" >PCB Impedance Calculator: Compare Finished Cross Sections<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-5\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#Impedance_Test_Coupon_vs_a_Region-Matched_Witness_Line\" >Impedance Test Coupon vs. a Region-Matched Witness Line<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-6\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#PCB_Cross_Section_Use_a_Paired_Measurement_Record\" >PCB Cross Section: Use a Paired Measurement Record<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-7\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#When_PCB_Copper_Thieving_Helps%E2%80%94and_When_It_Does_Not\" >When PCB Copper Thieving Helps\u2014and When It Does Not<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-8\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#PCB_Copper_Balance_How_to_Verify_the_Next_Build\" >PCB Copper Balance: How to Verify the Next Build<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-9\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#PCB_Copper_Density_and_Impedance_FAQs\" >PCB Copper Density and Impedance FAQs<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-10\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#Technical_References\" >Technical References<\/a><\/li><li class='ez-toc-page-1 ez-toc-heading-level-2'><a class=\"ez-toc-link ez-toc-heading-11\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#Custom_Controlled-Impedance_PCBs_With_Stackup_Review\" >Custom Controlled-Impedance PCBs With Stackup Review<\/a><\/li><\/ul><\/nav><\/div>\n<div class=\"yzp-no-index\"><\/div><p>Two PCB traces can have the same width in the artwork and still measure different impedances. If the difference follows a boundary between dense and sparse copper, compare the <strong>finished trace geometry and pressed dielectric thickness<\/strong> in both regions. A passing panel-rail coupon can confirm its own construction; it cannot settle that comparison unless it represents the same local conditions.<\/p>\n<p>The practical test is to compare two accessible lines with the same intended geometry and return path, then section both locations. Check the return path first: a missing reference plane changes the electrical structure even if lamination was perfect.<\/p>\n<figure><img loading=\"lazy\" decoding=\"async\" src=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2026\/11\/pcb-copper-density.jpg\" width=\"1200\" height=\"600\" style=\"max-width:100%;height:auto\" alt=\"Illustrated bare PCB showing sparse routed copper alongside a dense copper area\"><figcaption>Illustration: sparse routing and a dense copper region can share one PCB without sharing the same local lamination conditions.<\/figcaption><\/figure>\n<h2><span class=\"ez-toc-section\" id=\"What_Is_PCB_Copper_Density_Near_a_Trace\"><\/span>What Is PCB Copper Density Near a Trace?<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>For this check, PCB copper density is the percentage of a defined area occupied by copper on a specified layer. It is not copper weight, the density of the metal, or the amount of current a trace carries. Use the released fabrication artwork, including approved fill, and report the size and location of each measurement window. Comparing a small cutout on one layer with a whole-board average on another will hide the difference you want to see.<\/p>\n<p>Start with identical windows around the two trace regions, using the same window dimensions and the same layer. In an illustrative 10 mm by 10 mm window, 80 mm\u00b2 of copper gives 80% coverage and 25 mm\u00b2 gives 25%: a difference of 55 percentage points. That window size is for arithmetic, not a process rule. Ask the fabricator what scale reflects the construction; retain wider context if the nearby copper boundary is large or irregular.<\/p>\n<figure><img loading=\"lazy\" decoding=\"async\" src=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2026\/11\/pcb-copper-density-windows.jpg\" width=\"1200\" height=\"540\" style=\"max-width:100%;height:auto\" alt=\"Two equal-sized copper coverage windows with different proportions of solid copper\"><figcaption>Compare equal-size windows on the same layer. The patterns are schematic, not the 80% and 25% examples above. Keep the full artwork with your annotated windows so that a nearby boundary is not lost.<\/figcaption><\/figure>\n<h2><span class=\"ez-toc-section\" id=\"Why_Pressed_Prepreg_Thickness_Can_Change_Locally\"><\/span>Why Pressed Prepreg Thickness Can Change Locally<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Prepreg contains glass reinforcement and partially cured resin. Under heat and pressure, some resin moves into spaces beside the copper before curing. A wide sparse region and a dense region therefore need not press to the same local thickness. The glass reinforcement, available resin, copper height, fill pattern and layup affect the result; the copper-area percentage alone does not predict a pressed thickness.<\/p>\n<p>Gary Brist\u2019s published four-layer Partial POOL example reported a roughly 20\u201325% thickness reduction for the dielectric associated with the lines inset on layer 3. The study also observed a different thickness response on another layer pair. That is a measured result for that construction, not a general adjustment to put into a PCB stackup. In a new design, establish the direction and size from the actual layer pair.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"PCB_Stackup_Separate_Lamination_From_Return-Path_Changes\"><\/span>PCB Stackup: Separate Lamination From Return-Path Changes<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Compare the reference geometry before attributing a low or high reading to resin movement. A plane split directly under a route changes the return path; unmodeled copper beside a route can change coupling; a change in pressed spacing changes the cross-section even when the plane remains solid. More than one can occur at the same location.<\/p>\n<figure class=\"wp-block-table\">\n<table>\n<tbody>\n<tr>\n<td><strong>What changed?<\/strong><\/td>\n<td><strong>First useful evidence<\/strong><\/td>\n<td><strong>What to do next<\/strong><\/td>\n<\/tr>\n<tr>\n<td>Pressed signal-to-plane spacing<\/td>\n<td>Same-layer sections show different spacing, comparable finished width and the same reference geometry<\/td>\n<td>Use measured spacing in separate models. Repeat sections if one cut may not represent the region.<\/td>\n<\/tr>\n<tr>\n<td>Finished trace geometry<\/td>\n<td>Sections show different top or base width or copper thickness<\/td>\n<td>Compare process and artwork before changing the prepreg specification.<\/td>\n<\/tr>\n<tr>\n<td>Return or lateral coupling<\/td>\n<td>Artwork shows a plane gap, unmodeled nearby copper, or a changed pair spacing<\/td>\n<td>Model that geometry separately or change the route. A uniform-line calculation will not explain a transition.<\/td>\n<\/tr>\n<\/tbody>\n<\/table>\n<\/figure>\n<h2><span class=\"ez-toc-section\" id=\"PCB_Impedance_Calculator_Compare_Finished_Cross_Sections\"><\/span>PCB Impedance Calculator: Compare Finished Cross Sections<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Use a field solver to compare the two measured cross sections. Hold material assumptions and signal\/return topology constant for the first run; vary only the measured signal-to-plane gap. Then add the measured conductor sizes, differential spacing, solder mask and adjacent copper where relevant. For an ordinary microstrip with unchanged width, copper thickness and dielectric properties, moving the reference plane closer tends to lower impedance. When those other inputs also change, the size and even the net direction of the measured change cannot be inferred from copper density alone.<\/p>\n<p>Compare the direction and approximate magnitude with your measurements, and write down what the model omits. If a uniform cross-section model does not explain an abrupt feature, do not tune a single dielectric constant until it fits. Check the artwork for a transition, then use a suitable discontinuity model or a purpose-built sample.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"Impedance_Test_Coupon_vs_a_Region-Matched_Witness_Line\"><\/span>Impedance Test Coupon vs. a Region-Matched Witness Line<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Use a conventional rail coupon for agreed production checks and a region-matched witness line when the board has an electrically important density transition that the rail does not reproduce. A useful witness line keeps the same signal and reference layers, line geometry, material construction and local copper surroundings. Agree with the fabricator how to make it accessible, sufficiently long for measurement, and representative of its intended location. The witness line does not replace an actual channel test.<\/p>\n<p>For a controlled comparison, use equivalent launches, the same instrument calibration and rise-time setting, and a comparable stable measurement region. Repeat the contact and capture the raw traces. If the observed difference appears only around the launch or shifts on reconnect, investigate the setup first. The production measurement method IPC-TM-650 2.5.5.7, Rev A (March 2004), discusses representative specimens in \u00a7\u00a73.1.1\u20133.1.3 and describes limits on positional profiling in \u00a71.2(f). Apply the revision and acceptance criteria required by your order; do not take an arbitrary dip on a diagnostic TDR plot as an acceptance measurement. For record-level checks, use the <a href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-impedance-test-report\/\">PCB impedance test report guide<\/a>.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"PCB_Cross_Section_Use_a_Paired_Measurement_Record\"><\/span>PCB Cross Section: Use a Paired Measurement Record<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Choose marked locations in both regions, measure the witness lines first, and take cross sections from agreed sacrificial samples. Record the board or panel ID, region coordinates and layer pair. On each section, record the signal-to-reference spacing, the trace\u2019s top and base widths and its copper thickness. For stripline, record the distances to both reference planes. A single overall board-thickness measurement cannot substitute for these readings.<\/p>\n<figure><img loading=\"lazy\" decoding=\"async\" src=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2026\/11\/pcb-copper-density-section.jpg\" width=\"1200\" height=\"540\" style=\"max-width:100%;height:auto\" alt=\"Two simplified microstrip sections with the dielectric distance bracketed from the trace underside to the reference plane\"><figcaption>For this microstrip comparison, measure the dielectric from the underside of the trace to the facing surface of the reference plane. Sections are schematic and not to scale.<\/figcaption><\/figure>\n<p>Use the worksheet below when a repeatable impedance difference remains after the fixture check. Replace the example columns with readings from a matched pair, calculate B minus A, and ask whether the evidence justifies a lamination, geometry or electrical investigation. All entries below are hypothetical and independent; the dielectric column was not calculated from copper coverage, and impedance was not calculated from dielectric thickness.<\/p>\n<figure class=\"wp-block-table\">\n<table>\n<tbody>\n<tr>\n<td><strong>Input<\/strong><\/td>\n<td><strong>A: dense<\/strong><\/td>\n<td><strong>B: sparse<\/strong><\/td>\n<td><strong>B minus A<\/strong><\/td>\n<\/tr>\n<tr>\n<td>Same-layer copper coverage<\/td>\n<td>80%<\/td>\n<td>25%<\/td>\n<td>\u221255 percentage points<\/td>\n<\/tr>\n<tr>\n<td>Finished dielectric spacing<\/td>\n<td>100 \u00b5m<\/td>\n<td>80 \u00b5m<\/td>\n<td>\u221220 \u00b5m (\u221220% relative to A)<\/td>\n<\/tr>\n<tr>\n<td>Stable TDR reading<\/td>\n<td>50.2 \u03a9<\/td>\n<td>46.7 \u03a9<\/td>\n<td>\u22123.5 \u03a9<\/td>\n<\/tr>\n<\/tbody>\n<\/table>\n<\/figure>\n<p><strong>How to use the last row:<\/strong> if the agreed 50 \u03a9 \u00b15% range applies to these witness lines, its limits are 47.5\u201352.5 \u03a9. A is inside; B reads 0.8 \u03a9 below the lower limit. Check the agreed decision rule and measurement uncertainty before disposition. If repeat measurements and sections support the difference, verify that finished geometry and return paths really match, then test whether the spacing difference explains enough of the shift. If the setup varies by an amount comparable with the 3.5 \u03a9 separation, fix the measurement before asking the fabricator to change the layup.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"When_PCB_Copper_Thieving_Helps%E2%80%94and_When_It_Does_Not\"><\/span>When PCB Copper Thieving Helps\u2014and When It Does Not<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Filling a sparse region can help with some manufacturing nonuniformity, but added copper close to an impedance-controlled route can also change the electric field. Before releasing CAM edits, distinguish off-board fill for panel processing from copper inside the finished outline. Mark controlled routes and structures that require a keepout, then agree the boundary with the fabricator and confirm it in the model. There is no one clearance suitable for every stackup.<\/p>\n<p>Do not blanket-fill a plane opening reserved by the electrical design. If local fill is not allowed, compare moving the route, changing the reference arrangement or adjusting the layup. Keep changes separate on the qualification panel so they can be evaluated rather than hidden in a global trace-width change.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"PCB_Copper_Balance_How_to_Verify_the_Next_Build\"><\/span>PCB Copper Balance: How to Verify the Next Build<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Repeat the same regional comparison after an approved change. For a memory bus next to a copper boundary, check selected lines in both neighborhoods instead of averaging every line on the panel. For an RF route next to proposed fill, confirm the same measurement planes and compare the response across the specified frequency band; a coupon reading alone will miss a launch or a local coupling change. For routine lot release, use the approved sampling plan and the limits stated on the drawing or order, not the example numbers above.<\/p>\n<p>Record which artwork and stackup were actually built, where each sample came from, the instrument settings and what changed in CAM. Close the investigation when the region-specific evidence meets the agreed criteria and can be repeated. A smaller A\/B difference is not enough if both regions are still out of tolerance.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"PCB_Copper_Density_and_Impedance_FAQs\"><\/span>PCB Copper Density and Impedance FAQs<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<h3>Does doubling the copper coverage halve the impedance?<\/h3>\n<p>No. Coverage is an area ratio, while impedance depends on the finished transmission-line geometry and dielectric properties. Two layouts with the same percentage can place copper at very different distances from a route.<\/p>\n<h3>Can I use the same percentage target on every layer?<\/h3>\n<p>Do not assume that. A mostly solid reference plane and a routing layer have different functions. Document the neighborhood of the controlled line and ask which areas the fabricator wants to balance for that stackup.<\/p>\n<h3>Is a nominal prepreg thickness enough for a quote?<\/h3>\n<p>It is useful for discussion, but review the proposed finished dielectric spacing for each critical layer pair and how it will be verified. A prepreg style or catalog value does not establish that spacing in two very different copper environments.<\/p>\n<h3>Can a coupon from the panel edge stand in for the center?<\/h3>\n<p>Only for the conditions it has been shown to represent. Record the positions of the rail coupon and product regions, then compare them on a qualification build if the correlation is material to acceptance.<\/p>\n<h3>Do I need to cut every production panel?<\/h3>\n<p>No general rule requires that. Use agreed sacrificial specimens for engineering comparisons and retain the sampling frequency defined for production. Do not use one successful comparison to remove a contractual control.<\/p>\n<h3>What if the dielectric spacing is the same but the TDR readings differ?<\/h3>\n<p>Look at the finished top and base widths, copper thickness, mask, pair gap and adjacent copper. Then repeat the measurements with equivalent launches. Matching thickness removes one candidate explanation, not all of them.<\/p>\n<h3>What if the trace is too short to give a stable TDR region?<\/h3>\n<p>Design a longer accessible representative line or use an appropriate characterized fixture. Do not average a region dominated by the launch and termination just to obtain an impedance number.<\/p>\n<h3>Can an A\/B cross section prove my finished assembly will work?<\/h3>\n<p>No. It can show a geometric difference and help interpret a matched transmission-line measurement. An assembled channel still needs its own verification for losses, reflections and the requirements of the interface.<\/p>\n<h2><span class=\"ez-toc-section\" id=\"Technical_References\"><\/span>Technical References<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<ul>\n<li><a href=\"https:\/\/www.ipc.org\/system\/files\/technical_resource\/E5%26S07_01.pdf\" rel=\"nofollow\">Gary Brist: PCB Trace Impedance\u2014Impact of Localized PCB Copper Density<\/a>, four-layer case study and coupon comparison.<\/li>\n<li><a href=\"https:\/\/www.ipc.org\/sites\/default\/files\/test_methods_docs\/2-5-5-7a.pdf\" rel=\"nofollow\">IPC-TM-650 2.5.5.7, Revision A<\/a>, \u00a7\u00a71.2 and 3.1 for method and specimen scope.<\/li>\n<li><a href=\"https:\/\/www.altium.com\/documentation\/altium-designer\/pcb\/high-speed-design\/interactively-routing-controlled-impedance\" rel=\"nofollow\">Altium: Controlled Impedance Routing<\/a>, transmission-line geometry and reference-plane inputs.<\/li>\n<li><a href=\"https:\/\/www.polarinstruments.com\/support\/cits\/AP132.html\" rel=\"nofollow\">Polar Instruments AP132: Controlled Impedance\u2014Design for Test<\/a>, planning for representative and accessible test traces.<\/li>\n<\/ul>\n<h2><span class=\"ez-toc-section\" id=\"Custom_Controlled-Impedance_PCBs_With_Stackup_Review\"><\/span>Custom Controlled-Impedance PCBs With Stackup Review<span class=\"ez-toc-section-end\"><\/span><\/h2>\n<p>Get the production stackup and impedance test plan aligned before releasing your PCB order. EBest Circuit can review your fabrication drawings and proposed stackup, and discuss which coupon structures and reports should be included in your quote. That gives your engineering and quality teams the same layer-by-layer record before the boards are built.<\/p>\n<p>Send your Gerbers or ODB++ files, the drawing revision, target impedances and tolerances, and any locations where copper fill or plane clearance is restricted to <a href=\"mailto:sales@bestpcbs.com\">sales@bestpcbs.com<\/a>. Ask for a controlled-impedance PCB quote with the proposed stackup and agreed test evidence listed.<\/p>\n","protected":false},"excerpt":{"rendered":"<p>Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.<\/p>\n","protected":false},"author":32827,"featured_media":39154,"comment_status":"open","ping_status":"","sticky":false,"template":"","format":"standard","meta":{"_acf_changed":false,"_uf_show_specific_survey":0,"_uf_disable_surveys":false,"footnotes":""},"categories":[174],"tags":[6904,2094,3411,9453],"class_list":["post-39157","post","type-post","status-publish","format-standard","hentry","category-bestpcb","tag-controlled-impedance","tag-pcb-copper-density","tag-pcb-cross-section","tag-pcb-lamination"],"acf":[],"aioseo_notices":[],"aioseo_head":"\n\t\t<!-- All in One SEO 5.0.4 - aioseo.com -->\n\t<meta name=\"description\" content=\"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.\" \/>\n\t<meta name=\"robots\" content=\"max-image-preview:large\" \/>\n\t<meta name=\"author\" content=\"mingling, gong\"\/>\n\t<link rel=\"canonical\" href=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/\" \/>\n\t\t<meta name=\"generator\" content=\"All in One SEO (AIOSEO) 5.0.4\" \/>\n\t\t<meta property=\"og:locale\" content=\"en_US\" \/>\n\t\t<meta property=\"og:site_name\" content=\"PCB &amp; MCPCB - EBest PCB - More Technical Details &amp; News on PCB, MCPCB &amp; Ceramic PCB from EBest PCB\" \/>\n\t\t<meta property=\"og:type\" content=\"article\" \/>\n\t\t<meta property=\"og:title\" content=\"PCB Copper Density: Why Matching Traces Measure Differently - PCB &amp; MCPCB - EBest PCB\" \/>\n\t\t<meta property=\"og:description\" content=\"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.\" \/>\n\t\t<meta property=\"og:url\" content=\"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/\" \/>\n\t\t<meta property=\"og:image\" content=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2025\/08\/logo.png\" \/>\n\t\t<meta property=\"og:image:secure_url\" content=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2025\/08\/logo.png\" \/>\n\t\t<meta property=\"article:published_time\" content=\"2026-11-16T12:44:44+00:00\" \/>\n\t\t<meta property=\"article:modified_time\" content=\"2026-11-16T12:44:44+00:00\" \/>\n\t\t<meta property=\"article:publisher\" content=\"https:\/\/www.facebook.com\/Bestpcbs1\" \/>\n\t\t<meta name=\"twitter:card\" content=\"summary_large_image\" \/>\n\t\t<meta name=\"twitter:site\" content=\"@bestpcbs\" \/>\n\t\t<meta name=\"twitter:title\" content=\"PCB Copper Density: Why Matching Traces Measure Differently - PCB &amp; MCPCB - EBest PCB\" \/>\n\t\t<meta name=\"twitter:description\" content=\"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.\" \/>\n\t\t<meta name=\"twitter:creator\" content=\"@bestpcbs\" \/>\n\t\t<meta name=\"twitter:image\" content=\"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2016\/02\/logo.gif\" \/>\n\t\t<script type=\"application\/ld+json\" class=\"aioseo-schema\">\n\t\t\t{\"@context\":\"https:\\\/\\\/schema.org\",\"@graph\":[{\"@type\":\"BlogPosting\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#blogposting\",\"name\":\"PCB Copper Density: Why Matching Traces Measure Differently - PCB & MCPCB - EBest PCB\",\"headline\":\"PCB Copper Density: Why Matching Traces Measure Differently\",\"author\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/author\\\/gong588\\\/#author\"},\"publisher\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#organization\"},\"image\":{\"@type\":\"ImageObject\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/wp-content\\\/uploads\\\/2026\\\/11\\\/pcb-copper-density.jpg\",\"width\":1200,\"height\":600},\"datePublished\":\"2026-11-16T20:44:44+08:00\",\"dateModified\":\"2026-11-16T20:44:44+08:00\",\"inLanguage\":\"en-US\",\"mainEntityOfPage\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#webpage\"},\"isPartOf\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#webpage\"},\"articleSection\":\"bestpcb, controlled impedance, pcb copper density, PCB Cross Section, PCB lamination\"},{\"@type\":\"BreadcrumbList\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#breadcrumblist\",\"itemListElement\":[{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#listItem\",\"position\":1,\"name\":\"Home\",\"item\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/\",\"nextItem\":{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/category\\\/bestpcb\\\/#listItem\",\"name\":\"bestpcb\"}},{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/category\\\/bestpcb\\\/#listItem\",\"position\":2,\"name\":\"bestpcb\",\"item\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/category\\\/bestpcb\\\/\",\"nextItem\":{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#listItem\",\"name\":\"PCB Copper Density: Why Matching Traces Measure Differently\"},\"previousItem\":{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#listItem\",\"name\":\"Home\"}},{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#listItem\",\"position\":3,\"name\":\"PCB Copper Density: Why Matching Traces Measure Differently\",\"previousItem\":{\"@type\":\"ListItem\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/category\\\/bestpcb\\\/#listItem\",\"name\":\"bestpcb\"}}]},{\"@type\":\"Organization\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#organization\",\"name\":\"PCB & MCPCB - Best Technology\",\"description\":\"More Technical Details & News on PCB, MCPCB & Ceramic PCB from EBest PCB\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/\",\"telephone\":\"+8675529091601\",\"logo\":{\"@type\":\"ImageObject\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/wp-content\\\/uploads\\\/2025\\\/08\\\/logo.png\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#organizationLogo\"},\"image\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#organizationLogo\"},\"sameAs\":[\"https:\\\/\\\/www.facebook.com\\\/Bestpcbs1\",\"https:\\\/\\\/twitter.com\\\/bestpcbs\",\"https:\\\/\\\/www.youtube.com\\\/channel\\\/UCJsTR02i6mtLFnBBNC_i4bQ\\\/featured\",\"https:\\\/\\\/www.linkedin.com\\\/company\\\/best-pcb-technology\"]},{\"@type\":\"Person\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/author\\\/gong588\\\/#author\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/author\\\/gong588\\\/\",\"name\":\"mingling, gong\",\"image\":{\"@type\":\"ImageObject\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#authorImage\",\"url\":\"https:\\\/\\\/secure.gravatar.com\\\/avatar\\\/37717913504b7ea1df97ec73d58a7bcc?s=96&d=mm&r=g\",\"width\":96,\"height\":96,\"caption\":\"mingling, gong\"}},{\"@type\":\"WebPage\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#webpage\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/\",\"name\":\"PCB Copper Density: Why Matching Traces Measure Differently - PCB & MCPCB - EBest PCB\",\"description\":\"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.\",\"inLanguage\":\"en-US\",\"isPartOf\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#website\"},\"breadcrumb\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#breadcrumblist\"},\"author\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/author\\\/gong588\\\/#author\"},\"creator\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/author\\\/gong588\\\/#author\"},\"image\":{\"@type\":\"ImageObject\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/wp-content\\\/uploads\\\/2026\\\/11\\\/pcb-copper-density.jpg\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#mainImage\",\"width\":1200,\"height\":600},\"primaryImageOfPage\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/2026\\\/11\\\/pcb-copper-density-impedance\\\/#mainImage\"},\"datePublished\":\"2026-11-16T20:44:44+08:00\",\"dateModified\":\"2026-11-16T20:44:44+08:00\"},{\"@type\":\"WebSite\",\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#website\",\"url\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/\",\"name\":\"PCB & MCPCB - Best Technology\",\"description\":\"More Technical Details & News on PCB, MCPCB & Ceramic PCB from EBest PCB\",\"inLanguage\":\"en-US\",\"publisher\":{\"@id\":\"https:\\\/\\\/www.bestpcbs.com\\\/blog\\\/#organization\"}}]}\n\t\t<\/script>\n\t\t<!-- All in One SEO -->\n\n","aioseo_head_json":{"title":"PCB Copper Density: Why Matching Traces Measure Differently - PCB & MCPCB - EBest PCB","description":"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.","canonical_url":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/","robots":"max-image-preview:large","keywords":"","webmasterTools":{"miscellaneous":""},"schema":{"@context":"https:\/\/schema.org","@graph":[{"@type":"BlogPosting","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#blogposting","name":"PCB Copper Density: Why Matching Traces Measure Differently - PCB & MCPCB - EBest PCB","headline":"PCB Copper Density: Why Matching Traces Measure Differently","author":{"@id":"https:\/\/www.bestpcbs.com\/blog\/author\/gong588\/#author"},"publisher":{"@id":"https:\/\/www.bestpcbs.com\/blog\/#organization"},"image":{"@type":"ImageObject","url":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2026\/11\/pcb-copper-density.jpg","width":1200,"height":600},"datePublished":"2026-11-16T20:44:44+08:00","dateModified":"2026-11-16T20:44:44+08:00","inLanguage":"en-US","mainEntityOfPage":{"@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#webpage"},"isPartOf":{"@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#webpage"},"articleSection":"bestpcb, controlled impedance, pcb copper density, PCB Cross Section, PCB lamination"},{"@type":"BreadcrumbList","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#breadcrumblist","itemListElement":[{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/#listItem","position":1,"name":"Home","item":"https:\/\/www.bestpcbs.com\/blog\/","nextItem":{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/#listItem","name":"bestpcb"}},{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/#listItem","position":2,"name":"bestpcb","item":"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/","nextItem":{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#listItem","name":"PCB Copper Density: Why Matching Traces Measure Differently"},"previousItem":{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/#listItem","name":"Home"}},{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#listItem","position":3,"name":"PCB Copper Density: Why Matching Traces Measure Differently","previousItem":{"@type":"ListItem","@id":"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/#listItem","name":"bestpcb"}}]},{"@type":"Organization","@id":"https:\/\/www.bestpcbs.com\/blog\/#organization","name":"PCB & MCPCB - Best Technology","description":"More Technical Details & News on PCB, MCPCB & Ceramic PCB from EBest PCB","url":"https:\/\/www.bestpcbs.com\/blog\/","telephone":"+8675529091601","logo":{"@type":"ImageObject","url":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2025\/08\/logo.png","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#organizationLogo"},"image":{"@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#organizationLogo"},"sameAs":["https:\/\/www.facebook.com\/Bestpcbs1","https:\/\/twitter.com\/bestpcbs","https:\/\/www.youtube.com\/channel\/UCJsTR02i6mtLFnBBNC_i4bQ\/featured","https:\/\/www.linkedin.com\/company\/best-pcb-technology"]},{"@type":"Person","@id":"https:\/\/www.bestpcbs.com\/blog\/author\/gong588\/#author","url":"https:\/\/www.bestpcbs.com\/blog\/author\/gong588\/","name":"mingling, gong","image":{"@type":"ImageObject","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#authorImage","url":"https:\/\/secure.gravatar.com\/avatar\/37717913504b7ea1df97ec73d58a7bcc?s=96&d=mm&r=g","width":96,"height":96,"caption":"mingling, gong"}},{"@type":"WebPage","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#webpage","url":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/","name":"PCB Copper Density: Why Matching Traces Measure Differently - PCB & MCPCB - EBest PCB","description":"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.","inLanguage":"en-US","isPartOf":{"@id":"https:\/\/www.bestpcbs.com\/blog\/#website"},"breadcrumb":{"@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#breadcrumblist"},"author":{"@id":"https:\/\/www.bestpcbs.com\/blog\/author\/gong588\/#author"},"creator":{"@id":"https:\/\/www.bestpcbs.com\/blog\/author\/gong588\/#author"},"image":{"@type":"ImageObject","url":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2026\/11\/pcb-copper-density.jpg","@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#mainImage","width":1200,"height":600},"primaryImageOfPage":{"@id":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/#mainImage"},"datePublished":"2026-11-16T20:44:44+08:00","dateModified":"2026-11-16T20:44:44+08:00"},{"@type":"WebSite","@id":"https:\/\/www.bestpcbs.com\/blog\/#website","url":"https:\/\/www.bestpcbs.com\/blog\/","name":"PCB & MCPCB - Best Technology","description":"More Technical Details & News on PCB, MCPCB & Ceramic PCB from EBest PCB","inLanguage":"en-US","publisher":{"@id":"https:\/\/www.bestpcbs.com\/blog\/#organization"}}]},"og:locale":"en_US","og:site_name":"PCB &amp; MCPCB - EBest PCB - More Technical Details &amp; News on PCB, MCPCB &amp; Ceramic PCB from EBest PCB","og:type":"article","og:title":"PCB Copper Density: Why Matching Traces Measure Differently - PCB &amp; MCPCB - EBest PCB","og:description":"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.","og:url":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/","og:image":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2025\/08\/logo.png","og:image:secure_url":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2025\/08\/logo.png","article:published_time":"2026-11-16T12:44:44+00:00","article:modified_time":"2026-11-16T12:44:44+00:00","article:publisher":"https:\/\/www.facebook.com\/Bestpcbs1","twitter:card":"summary_large_image","twitter:site":"@bestpcbs","twitter:title":"PCB Copper Density: Why Matching Traces Measure Differently - PCB &amp; MCPCB - EBest PCB","twitter:description":"Find out how local PCB copper density changes pressed dielectric thickness, and use paired TDR tests and cross sections to check an impedance shift.","twitter:creator":"@bestpcbs","twitter:image":"https:\/\/www.bestpcbs.com\/blog\/wp-content\/uploads\/2016\/02\/logo.gif"},"aioseo_meta_data":{"post_id":"39157","title":null,"description":null,"keywords":null,"keyphrases":null,"primary_term":null,"canonical_url":null,"og_title":null,"og_description":null,"og_object_type":"default","og_image_type":"default","og_image_url":null,"og_image_width":null,"og_image_height":null,"og_image_custom_url":null,"og_image_custom_fields":null,"og_video":null,"og_custom_url":null,"og_article_section":null,"og_article_tags":null,"twitter_use_og":false,"twitter_card":"default","twitter_image_type":"default","twitter_image_url":null,"twitter_image_custom_url":null,"twitter_image_custom_fields":null,"twitter_title":null,"twitter_description":null,"schema":{"blockGraphs":[],"customGraphs":[],"default":{"data":{"Article":[],"Course":[],"Dataset":[],"FAQPage":[],"Movie":[],"Person":[],"Product":[],"ProductReview":[],"Car":[],"Recipe":[],"Service":[],"SoftwareApplication":[],"WebPage":[]},"graphName":"BlogPosting","isEnabled":true},"graphs":[]},"schema_type":"default","schema_type_options":null,"pillar_content":false,"robots_default":true,"robots_noindex":false,"robots_noarchive":false,"robots_nosnippet":false,"robots_nofollow":false,"robots_noimageindex":false,"robots_noodp":false,"robots_notranslate":false,"robots_max_snippet":null,"robots_max_videopreview":null,"robots_max_imagepreview":"large","priority":null,"frequency":null,"local_seo":null,"breadcrumb_settings":null,"limit_modified_date":false,"ai":null,"created":"2026-11-16 12:44:48","updated":"2026-11-16 12:49:04","seo_analyzer_scan_date":null,"focus_keyword":null,"additional_keywords":null,"truseo_locale":null},"aioseo_breadcrumb":"<div class=\"aioseo-breadcrumbs\"><span class=\"aioseo-breadcrumb\">\n\t\t\t<a href=\"https:\/\/www.bestpcbs.com\/blog\/\" title=\"Home\">Home<\/a>\n\t\t<\/span><span class=\"aioseo-breadcrumb-separator\">\u00bb<\/span><span class=\"aioseo-breadcrumb\">\n\t\t\t<a href=\"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/\" title=\"bestpcb\">bestpcb<\/a>\n\t\t<\/span><span class=\"aioseo-breadcrumb-separator\">\u00bb<\/span><span class=\"aioseo-breadcrumb\">\n\t\t\tPCB Copper Density: Why Matching Traces Measure Differently\n\t\t<\/span><\/div>","aioseo_breadcrumb_json":[{"label":"Home","link":"https:\/\/www.bestpcbs.com\/blog\/"},{"label":"bestpcb","link":"https:\/\/www.bestpcbs.com\/blog\/category\/bestpcb\/"},{"label":"PCB Copper Density: Why Matching Traces Measure Differently","link":"https:\/\/www.bestpcbs.com\/blog\/2026\/11\/pcb-copper-density-impedance\/"}],"_links":{"self":[{"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/posts\/39157","targetHints":{"allow":["GET"]}}],"collection":[{"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/posts"}],"about":[{"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/types\/post"}],"author":[{"embeddable":true,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/users\/32827"}],"replies":[{"embeddable":true,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/comments?post=39157"}],"version-history":[{"count":1,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/posts\/39157\/revisions"}],"predecessor-version":[{"id":39158,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/posts\/39157\/revisions\/39158"}],"wp:featuredmedia":[{"embeddable":true,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/media\/39154"}],"wp:attachment":[{"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/media?parent=39157"}],"wp:term":[{"taxonomy":"category","embeddable":true,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/categories?post=39157"},{"taxonomy":"post_tag","embeddable":true,"href":"https:\/\/www.bestpcbs.com\/blog\/wp-json\/wp\/v2\/tags?post=39157"}],"curies":[{"name":"wp","href":"https:\/\/api.w.org\/{rel}","templated":true}]}}